Pro/rNGINEER Wildfire Tips & Tutorial (Pro/E Wildfire 4.0, Wildfire 3.0, Wildfire 2.0 and 2001)

TUTORIAL: Create BOM Table in Pro/E Detailing

TUTORIAL: Create BOM Table in Pro/E Detailing

Version: Pro/E 2001, Wildfire, Wildfire2.0, Wildfire3.0

Pro/ENGINEER doesn’t provide any BOM table by default. Users may create your own BOM table or download from internet. This has caused inconvenient especially to the new Pro/E users. BOM table / parts list should be a standard item in MCAD 3D modeling software now days.

Proengineertips.com provides you with both of the options. You can learn how to create a BOM table from this tutorial and also you can also download BOM table here.

Below is a short tutorial for creating a BOM table in Pro/E Detailing (Drawing).

 

1. In Pro/E drawing mode, clicks Table > Insert > Table from the drop down menu

Pro/E insert table

2. Menu manager appears, click on the screen to draw a table. For this tutorial, we are creating table by Number of Characters

Pro/E insert table

3. After the 1st clicks, there are some numbers appears towards the right. These numbers basically represent number of characters. For the 1st column, I would like to have 4 characters. Move your mouse pointer to the spacing between 4 & 5 and click. Next, continue to create another 3 columns using the same method.

When you are done with the columns, hit MMB to define the rows. For BOM table in Pro/E, only 2 rows are required.

pro/E create BOM table

4. We are going to enter some text in a cell. Double clicks the cell and the Note Properties dialog box appears and type in the desired note. Say: ITEM and hit the OK button.

pro/E BOM table text

pro/E note properties dialog box

5. The table cell should now fill with text - ITEM. After that, continue to enter notes to the rest of the cells in the same row – DESCRIPTION, NAME, QTY

pro/E BOM table - ITEM

pro/E drawing BOM table

6. Next, we are going to create a repeat region in the table.

What is Repeat Region in Pro/E?

Repeat Region is dynamic report table cells which are based on the principle of "smart" table in Pro/E. Repeat regions can expand or contract by accommodating the amount of data that the associated model currently possesses.

To create repeat region, clicks Table > Repeat Region from the drop down menu

pro/E repeat region

7. Next, clicks Add in the menu manager and clicks the table cell (from –to) as shown in the following images.

 Pro/E repeat region

 Pro/E repeat region

 Pro/E repeat region

You should notice that the selected cells’ boundary turn to orange color. This is indicating the repeat region.

 Pro/E repeat region

8. Select the cell as shown below, press and hold RMB. Choose Report Parameter from the context sensitive menu.

 Pro/E repeat region Report Parameter

Report Symbol dialog box appears. Pick the desired symbol for the cell.

 Pro/E repeat region Report Parameter

I. rpt.index
II. asm.mbr.description (user defined)
III. asm.mbr.name
IV. rpt.qty

 Pro/E repeat region Report Parameter

9. After regenerate, your parts list will appears in the table. You can save the BOM table as a *.tbl file to use it in another Pro/E drawing.

Select any cell in the table, clicks Table > Save Table > As Table File from the drop down menu

 Pro/E save BOM table

Download: Pro/E BOM table file *.tbl (Top – Down: Downwards)
Download: Pro/E BOM table file *.tbl (Bottom – Up: Upwards)

To insert BOM table using the downloaded files in Pro/E, clicks Table > Insert > Table From File from the drop down menu. You may need to customise the BOM table to fit your company requirement.

 

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