Pro/rNGINEER Wildfire Tips & Tutorial (Pro/E Wildfire 4.0, Wildfire 3.0, Wildfire 2.0 and 2001)

TUTORIAL: Dimension Pattern in Pro/ENGINEER Wildfire (Angular Dimension)

TUTORIAL: Dimension Pattern in Pro/ENGINEER Wildfire (Angular Dimension)

Version: Pro/E Wildfire, Wildfire 2.0, Wildfire 3.0, Wildfire 4.0

This tutorial shows you the steps how to create a circular pattern using the dimension type pattern (angular) in Pro/ENGINEER Wildfire. Download the ProE part file used in the following dimension pattern tutorial here (ProE file: dimension pattern angular start.prt ).

Dimension Pattern in Pro/ENGINEER Wildfire - Angular done

1. Open the downloaded tutorial start file (dimension_pattern_angular_start.prt ). The ProE model should look like below.

Dimension Pattern in Pro/ENGINEER Wildfire - start

2. Select the hole feature which to be patterned. After that, press and hold RMB to access the context sensitive menu. Choose the Pattern command from the list.

Dimension Pattern in Pro/ENGINEER Wildfire - right menu command

3. Pattern dashboard will appear to you at the message area. Dimension type pattern is the default for pattern dashboard.

Dimension Pattern in Pro/ENGINEER Wildfire - dashboard

The dimensions of the hole feature will be displayed for you to select it as the 1st direction.

Dimension Pattern in Pro/ENGINEER Wildfire - dimension display

4. Select the angle dimension as shown in the image below (red) for the 1st direction. Input 45 degree and ENTER for the increment value for the 1st direction in the pattern. After that, Change the quantity to 8 instances.

1st direction for Dimension Pattern in Pro/ENGINEER Wildfire

The pattern instances will be represented as black dots for the preview purposes.

Dimension Pattern in Pro/ENGINEER Wildfire - 1 direction preview

5. Next, we need to activate the 2nd direction definition for Pro/E Wildfire pattern feature. Click the cell in the pattern dashboard as show in the image below.

activate 2nd direction in Pattern dashboard in Pro/ENGINEER Wildfire - dimensions

6. Repeat step 4 to define the 2nd direction for the pattern feature. (see image below)

2nd direction for Dimension Pattern in Pro/ENGINEER Wildfire

This time, we are controlling the PCD of the holes. Input 60 as the increment value and 4 in quantity. The Pro/E model should look like below at the end of step 6.

Dimension Pattern in Pro/ENGINEER Wildfire pattern preview

7. We are done with the tutorial, click the check mark Pro/E wildfire dashboard check - confirm button on the pattern dashboard to confirm the dimension pattern feature. A regeneration bar (WF2 and above) will appear to indicate the progress of the calculation.

ProE Wildfire 2.0 regeration progress bar for pattern feature

The image below shows you the final model for the dimension pattern (linear) in Pro/E Wildfire.

Dimension Pattern in Pro/ENGINEER Wildfire - done

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