Pro/rNGINEER Wildfire Tips & Tutorial (Pro/E Wildfire 4.0, Wildfire 3.0, Wildfire 2.0 and 2001)

TUTORIAL: Pro/E Wildfire Variable Section Sweep – Multiple Trajectory

TUTORIAL: Pro/E Wildfire Variable Section Sweep – Multiple Trajectory

Version: Pro/E Wildfire, Wildfire 2.0 and Wildfire 3.0

Pro/E Wildfire Variable Section Sweep feature can be created thru a few trajectories. Sketch by reference to the points on the trajectory will updates its shape thru sweep accordingly. This tool is very useful when you are handling some complicated / advanced surface.

The main objective of this tutorial is helping you to understand the work flow of Variable Section Sweep. A simple part file has created for this quick tutorial. Download the tutorial file here (multiple_traj.zip) before begin.

1. Extract the downloaded file and open multiple_traj_start.prt

proe wildfire variable section sweep tutorial

2. Click Insert > Variable Section Sweep from the menu or the pro/e wildfire variable section sweep icon icon to activate the Variable Section Sweep command. Next, select the all trajectories. Notes: Trajectory selected will turn into red.

proe wildfire variable section sweep tutorial - select trajectory

3. Click the sketch icon proe wildfire variable section sweep dashboard sketch icon on dashboard to start sketching. Alternatively, you can also press and hold the RMB and choose the sketch option from the drop down menu.

proe wildfire variable section sweep tutorial - right click menu

4. Entering the sketch mode, vertex (intersection between trajectory and sketching plane) is marked with small yellow cross. These vertexes should be used as the reference for your sketch. proe wildfire variable section sweep tutorial - sketch vertex

5. For this tutorial, let’s use the spline tool to connect all the vertexes together. When you are done, press the check icon proe sketcher check OK icon to confirm the sketch.

proe wildfire variable section sweep tutorial - sketch spline

6. In Pro/ENGINEER Wildfire, light weight preview for the Variable Section Sweep appears in the screen. The default section is always normal to the trajectory which is indicated with arrow.

proe wildfire variable section sweep tutorial - light weight preview (normal trajectory)

7. Now, we will need to change the Section Plane Control on the Variable Section Sweep dashboard. Change the setting to Constant Normal Direction.
proe wildfire variable section sweep tutorial - constant normal direction

8. After that, select the plane which is indicating the section direction. In this tutorial, I pick the TOP datum plane.

proe wildfire variable section sweep tutorial - select normal plane

9. The section plane is now constantly parallel to the TOP datum plane. Images below are the Pro/E Wildfire light weight preview and the final variable section sweep surface in shaded mode. You can open the multiple_traj_done.prt from the downloaded file to get the completed feature.

proe wildfire variable section sweep tutorial - light weight preview (constant normal dir)

proe wildfire variable section sweep tutorial - Shaded surface

Related Links:
What is Pro/ENGINEER Wildfire Variable Section Sweep?
TIPS: Pro/ENGINEER Wildfire Variable Section Sweep

Variable Section Control in Pro/E Variable Section Sweep feature with Evalgraph
TUTORIAL: Create CAM profile using Graph feature in Pro/E

Variable Section Control in Pro/E Variable Section Sweep feature with TRAJPAR equation
TUTORIAL: Pro/E Wildfire Variable Section Sweep - TRAJPAR equation

Section Plane Control in Pro/E Variable Section Sweep feature
TIPS: Pro/E Wildfire Variable Section Sweep – Section Plane Control

ProENGINEERtips.com is an independent website providing tips and tutorials for Pro/ENGINEER users.
ProENGINEER version covered: ProE 2001, Wildfire, wildfire 2.0, Wildfire 3.0 and Wildfire 4.0
Pro/ENGINEER Wildfire and Pro/INTRALINK are the registered trademark of PTC.
© 2006 - 2012 www.proengineertips.com

Top Desktop version